Fillet fails to update
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Fillet fails to update
Freecad version:
OS: Windows 10 Version 2009
Word size of OS: 64-bit
Word size of FreeCAD: 64-bit
Version: 0.19.24291 (Git)
Build type: Release
Branch: releases/FreeCAD-0-19
Hash: 7b5e18a0759de778b74d3a5c17eba9cb815035ac
Python version: 3.8.6+
Qt version: 5.15.2
Coin version: 4.0.1
OCC version: 7.5.0
Locale: Dutch/Netherlands (nl_NL)
After having less than 0 time to play with Freecad for a large amount of time I had a go again a couple of days ago.
I have created a little scoop 4 days ago. During its design I have not gotten errors, and even printed a version.
This evening however I wanted to change the length of the handle, and that is were things started to go weird.
I keep getting an error "failed to create fillet". Even if I now take the original design the first fillet (fillet 1mm) and do a re-calculation it will throw an error.
As said I opened the file I left a couple of days ago and all I did was "recalculate object"without changing a single thing. I have been searching the web and in freecad itself so see if I could find what could cause this, but I do not see what is going wrong. When I select the fillet ( fillet 1mm) then all 3 side show up nice in pink. everything seems to be a single piece, and as said I did not change a thing and did not get an error when I created the fillet nor a couple of other fillets after that.
I hope someone sees what I a doing wrong or what is going wrong
OS: Windows 10 Version 2009
Word size of OS: 64-bit
Word size of FreeCAD: 64-bit
Version: 0.19.24291 (Git)
Build type: Release
Branch: releases/FreeCAD-0-19
Hash: 7b5e18a0759de778b74d3a5c17eba9cb815035ac
Python version: 3.8.6+
Qt version: 5.15.2
Coin version: 4.0.1
OCC version: 7.5.0
Locale: Dutch/Netherlands (nl_NL)
After having less than 0 time to play with Freecad for a large amount of time I had a go again a couple of days ago.
I have created a little scoop 4 days ago. During its design I have not gotten errors, and even printed a version.
This evening however I wanted to change the length of the handle, and that is were things started to go weird.
I keep getting an error "failed to create fillet". Even if I now take the original design the first fillet (fillet 1mm) and do a re-calculation it will throw an error.
As said I opened the file I left a couple of days ago and all I did was "recalculate object"without changing a single thing. I have been searching the web and in freecad itself so see if I could find what could cause this, but I do not see what is going wrong. When I select the fillet ( fillet 1mm) then all 3 side show up nice in pink. everything seems to be a single piece, and as said I did not change a thing and did not get an error when I created the fillet nor a couple of other fillets after that.
I hope someone sees what I a doing wrong or what is going wrong
- Attachments
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- meelwormen schepje - V1.FCStd
- (89.06 KiB) Downloaded 47 times
- Shalmeneser
- Veteran
- Posts: 9585
- Joined: Wed Dec 23, 2020 12:04 am
- Location: Fr
Re: Fillet fails to update
* Open "Fillet 1mm" or 2mm or 5mm
* Close it with OK
* Last fillet fail
I think the problem is with Refine.
I don't know why there is yet a seam line underneath when all fillets are with Refine=true.
You should set Refine=true in the last Pad then correct all fillets (suppress + add).
* Close it with OK
* Last fillet fail
I think the problem is with Refine.
I don't know why there is yet a seam line underneath when all fillets are with Refine=true.
You should set Refine=true in the last Pad then correct all fillets (suppress + add).
Re: Fillet fails to update
The seam is properly removed here. OS: macOS 10.16Shalmeneser wrote: ↑Fri Oct 15, 2021 9:40 pm I don't know why there is yet a seam line underneath when all fillets are with Refine=true.
Word size of FreeCAD: 64-bit
Version: 0.20.25943 (Git)
Build type: Release
Branch: master
Hash: a65464b722a846bd2999aa2fecdff1132b15b297
Python version: 3.9.7
Qt version: 5.12.9
Coin version: 4.0.0
OCC version: 7.5.2
Locale: C/Default (C)
A Sketcher Lecture with in-depth information is available in English, auf Deutsch, en français, en español.
- Shalmeneser
- Veteran
- Posts: 9585
- Joined: Wed Dec 23, 2020 12:04 am
- Location: Fr
Re: Fillet fails to update
Fillet1mm with Refine=true shows seam in the original file.
This seam disapear after opening Fillet1mm and OK it, but after fillet2mm fails.
This seam disapear after opening Fillet1mm and OK it, but after fillet2mm fails.
- Attachments
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- Capture du 2021-10-16 00-19-30.png (42.52 KiB) Viewed 2072 times
Re: Fillet fails to update
That's probably due to the topological naming change.
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- Shalmeneser
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- Joined: Wed Dec 23, 2020 12:04 am
- Location: Fr
Re: Fillet fails to update
True, but why is the seam still visible with refine=true in the original file ?
Re: Fillet fails to update
That's a riddle to me.Shalmeneser wrote: ↑Sat Oct 16, 2021 8:01 am True, but why is the seam still visible with refine=true in the original file ?
I opened the file and did nothing but changing Refine=True for Fillet 1mm and making it visible. I upload the file in that state, please have a look and check if a recompute shows the seam again.
- Attachments
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- meelwormen_refined_cb.FCStd
- (74.94 KiB) Downloaded 33 times
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- Shalmeneser
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- Posts: 9585
- Joined: Wed Dec 23, 2020 12:04 am
- Location: Fr
Re: Fillet fails to update
Your file shows directly an under face without seam.
The original file with recompute hide the seam in Fillet1mm.
I thought changing Refine status would recompute the construction, hiding the seam (and failing latter fillets).
BTW, opening your file and rotating it shows weird view, like a cut in the view (picture).
- Attachments
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- Capture du 2021-10-16 11-33-50.png (5.18 KiB) Viewed 1878 times
Re: Fillet fails to update
That's what it does here if I leave the fieldShalmeneser wrote: ↑Sat Oct 16, 2021 9:43 am I thought changing Refine status would recompute the construction, hiding the seam (and failing latter fillets).
I don't know if it is in the file or just an unlucky coincidence of the camera position. A "Fit All" should fix this.BTW, opening your file and rotating it shows weird view, like a cut in the view (picture).
A Sketcher Lecture with in-depth information is available in English, auf Deutsch, en français, en español.
Re: Fillet fails to update
Sketch002 uses a zero dimension instead of a point-on-line constraint. When I fixed that problem the seam disappeared. Due to precision issues there really is a small step at that point.Shalmeneser wrote: ↑Sat Oct 16, 2021 8:01 am True, but why is the seam still visible with refine=true in the original file ?
Gene