Yes, indeed, you have imported svg.
In general, you need to convert each profile to a sketch. Unfortunately that isn't the end. The sketches have to be validated (and processed to get rid of extra line, non-coincident vertices, overlapping lines, etc.
To get this profile, I had to fix a bunch of non-coincident vertices, one overlapping line, and redundant lines. (Note, actually, there are no lines, all this geometry is imported as splines...even the straight lines.) Some of the non-coincident vertices were not even close to each other.
In all I did a lot of steps, to get this one model:
The step by step is something like this:
- import or open svg file.
- remove all unneeded geometry (text, other outlines, etc.)
- select the geometry that represents the outline to be modeled
- use the Draft workbench Convert to sketch
- if the sketch is to be used in Part Design, then create a body, drag the sketch into the body
- now attach the sketch to a base plane using the Part Design Map to face tool.
- now use the Validate sketch tool to find non-coincident vertices
- (the fix option might fix them all...but can't handle lines that are duplicates, they must be found and deleted.)
- since all geometry is splines, it might be good to change all the straight splines to lines
- some lines are segments of straight lines rather than on line. this will cause extra faces in the model, find and fix
- try to pad, if it fails go through previous steps, starting at #7 to fix geometry
Or, import the geometry, delete what you don't need, start a new Part Design sketch and trace over the svg geometry. Then delete the svg geometry.